boundaryFoam.C

Go to the documentation of this file.

/*---------------------------------------------------------------------------*\
  =========                 |
  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
   \\    /   O peration     |
    \\  /    A nd           | www.openfoam.com
     \\/     M anipulation  |
-------------------------------------------------------------------------------
    Copyright (C) 2011-2017 OpenFOAM Foundation
-------------------------------------------------------------------------------
License
    This file is part of OpenFOAM.
 
    OpenFOAM is free software: you can redistribute it and/or modify it
    under the terms of the GNU General Public License as published by
    the Free Software Foundation, either version 3 of the License, or
    (at your option) any later version.
 
    OpenFOAM is distributed in the hope that it will be useful, but WITHOUT
    ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or
    FITNESS FOR A PARTICULAR PURPOSE.  See the GNU General Public License
    for more details.
 
    You should have received a copy of the GNU General Public License
    along with OpenFOAM.  If not, see <http://www.gnu.org/licenses/>.
 
Application
    boundaryFoam
 
Group
    grpIncompressibleSolvers
 
Description
    Steady-state solver for incompressible, 1D turbulent flow,
    typically to generate boundary layer conditions at an inlet.
 
    Boundary layer code to calculate the U, k and epsilon distributions.
    Used to create inlet boundary conditions for experimental comparisons
    for which U and k have not been measured.
    Turbulence model is runtime selectable.
 
\*---------------------------------------------------------------------------*/
 
#include "fvCFD.H"
#include "singlePhaseTransportModel.H"
#include "turbulentTransportModel.H"
#include "fvOptions.H"
#include "wallFvPatch.H"
#include "makeGraph.H"
 
// * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
int main(int argc, char *argv[])
{
    argList::addNote
    (
        "Steady-state solver for incompressible, 1D turbulent flow,"
        " typically to generate boundary layer conditions at an inlet."
    );
 
    argList::noParallel();
    #include "addCheckCaseOptions.H"
 
    #include "setRootCaseLists.H"
    #include "createTime.H"
    #include "createMesh.H"
    #include "createFields.H"
    #include "interrogateWallPatches.H"
 
    turbulence->validate();
 
    // * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * * //
 
    Info<< "\nStarting time loop\n" << endl;
 
    while (runTime.loop())
    {
        Info<< "Time = " << runTime.timeName() << nl << endl;
 
        fvVectorMatrix divR(turbulence->divDevReff(U));
        divR.source() = flowMask & divR.source();
 
        fvVectorMatrix UEqn
        (
            divR == gradP + fvOptions(U)
        );
 
        UEqn.relax();
 
        fvOptions.constrain(UEqn);
 
        UEqn.solve();
 
        fvOptions.correct(U);
 
 
        // Correct driving force for a constant volume flow rate
        dimensionedVector UbarStar = flowMask & U.weightedAverage(mesh.V());
 
        U += (Ubar - UbarStar);
        gradP += (Ubar - UbarStar)/(1.0/UEqn.A())().weightedAverage(mesh.V());
 
        laminarTransport.correct();
        turbulence->correct();
 
        Info<< "Uncorrected Ubar = " << (flowDirection & UbarStar.value())
            << ", pressure gradient = " << (flowDirection & gradP.value())
            << endl;
 
        #include "evaluateNearWall.H"
 
        if (runTime.writeTime())
        {
            #include "makeGraphs.H"
        }
 
        runTime.printExecutionTime(Info);
    }
 
    Info<< "End\n" << endl;
 
    return 0;
}
 
 
// ************************************************************************* //