This boundary condition provides a coupled temperature condition between multiple mesh regions. More...

Inheritance diagram for thermalBaffleFvPatchScalarField:

Collaboration diagram for thermalBaffleFvPatchScalarField:

Public Member Functions
	TypeName ("compressible::thermalBaffle")
	Runtime type information. More...

	thermalBaffleFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	thermalBaffleFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	thermalBaffleFvPatchScalarField (const thermalBaffleFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given. More...

virtual tmp< fvPatchScalarField >	clone () const
	Construct and return a clone. More...

	thermalBaffleFvPatchScalarField (const thermalBaffleFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const
	Construct and return a clone setting internal field reference. More...

virtual void	autoMap (const fvPatchFieldMapper &)
	Map (and resize as needed) from self given a mapping object. More...

virtual void	rmap (const fvPatchScalarField &, const labelList &)
	Reverse map the given fvPatchField onto this fvPatchField. More...

virtual void	updateCoeffs ()
	Update the coefficients associated with the patch field. More...

virtual void	write (Ostream &) const
	Write. More...

Public Member Functions inherited from turbulentTemperatureRadCoupledMixedFvPatchScalarField
	TypeName ("compressible::turbulentTemperatureRadCoupledMixed")
	Runtime type information. More...

	turbulentTemperatureRadCoupledMixedFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	turbulentTemperatureRadCoupledMixedFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	turbulentTemperatureRadCoupledMixedFvPatchScalarField (const turbulentTemperatureRadCoupledMixedFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given. More...

	turbulentTemperatureRadCoupledMixedFvPatchScalarField (const turbulentTemperatureRadCoupledMixedFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

Public Member Functions inherited from temperatureCoupledBase
	temperatureCoupledBase (const fvPatch &patch, const word &calculationMethod, const word &kappaName, const word &alphaAniName, const word &alphaName)
	Construct from patch and K name. More...

	temperatureCoupledBase (const fvPatch &patch, const dictionary &dict)
	Construct from patch and dictionary. More...

	temperatureCoupledBase (const fvPatch &patch, const temperatureCoupledBase &base)
	Construct from patch and temperatureCoupledBase. More...

virtual	~temperatureCoupledBase ()=default
	Destructor. More...

word	KMethod () const
	Method to obtain K. More...

const word &	kappaName () const
	Name of thermal conductivity field. More...

const word &	alphaName () const
	Name of thermal diffusivity field. More...

virtual tmp< scalarField >	kappa (const scalarField &Tp) const
	Given patch temperature calculate corresponding K field. More...

virtual tmp< scalarField >	alpha (const scalarField &Tp) const
	Given patch temperature calculate corresponding alphaEff field. More...

void	write (Ostream &os) const
	Write. More...

Additional Inherited Members
Public Types inherited from temperatureCoupledBase
enum	KMethodType { mtFluidThermo, mtSolidThermo, mtDirectionalSolidThermo, mtLookup }
	Type of supplied Kappa. More...

Protected Attributes inherited from temperatureCoupledBase
const fvPatch &	patch_
	Underlying patch. More...

const KMethodType	method_
	How to get K. More...

const word	kappaName_
	Name of thermal conductivity field (if looked up from database) More...

const word	alphaAniName_
	Name of the non-Isotropic alpha (default: Anialpha) More...

const word	alphaName_
	Name of thermal diffusivity. More...

Static Protected Attributes inherited from temperatureCoupledBase
static const Enum< KMethodType >	KMethodTypeNames_

Detailed Description

This boundary condition provides a coupled temperature condition between multiple mesh regions.

The regions are generally referred to as the:

primary region,
and baffle region.

The primary region creates the baffle region and evolves its energy equation either:

1-D, normal to each patch face
3-D, normal and tangential components

The thermodynamic properties of the baffle material are specified via dictionary entries on the master patch.

The underlying polyPatch on the primary region needs to be defined as a complete mappedWall. i.e:

    type            mappedWall;
    sampleMode      nearestPatchFace;
    samplePatch     <patchName>;
    sampleRegion    <regionName>;

    coupleGroup     <coupleGroupName>;

The /keyword{internal} is true when the thermal baffle is used on internal faces and the baffle is coupled on both sides (bottom and top).

If this baffle is used on a patch set internal = false. By default is true.

Property	Description	Required	Default value
`Tnbr`	name of the field	no	T
`qrNbr`	name of the radiative flux in the nbr region	no	none
`qr`	name of the radiative flux in this region	no	none
`thicknessLayers`	inherited from temperatureCoupledBase	inherited
`kappaLayers`	inherited from temperatureCoupledBase	inherited
`kappaMethod`	inherited from temperatureCoupledBase	inherited
`kappa`	inherited from temperatureCoupledBase	inherited
`thermalInertia`	Add thermal inertia to wall node	no	false
`region`	Name of the solid region	yes
`active`	Active	yes
`internal`	Is the baffle an internal regiion	no	true
`thermoType`	Solid thermo type	yes
`mixture`	Mixture solid	yes
`radiation`	Radiation model in the solid	yes
`extrudeModel`	Extrude model	yes
`nLayers`	Number of cell across the ragion	yes
`expansionRatio`	Expansion ratio for the solid region	yes
`columnCells`	true for 1D or false for 3D region	yes

Usage

Example of the boundary condition specification:

<masterPatchName>
{
    type                compressible::thermalBaffle;

    // Underlying coupled boundary condition
    Tnbr               T;
    kappaMethod        fluidThermo; // or solidThermo
    kappa              none;
    qrNbr              qr;//or none.Name of qr field on neighbourregion
    qr                 none;// or none.Name of qr field on localregion
    value              uniform 300;

    // Baffle region name
    region              baffleRegion;
    active              yes;
    internal            yes;

    // Solid thermo in solid region
    thermoType
    {
        type            heSolidThermo;
        mixture         pureMixture;
        transport       constIso;
        thermo          hConst;
        equationOfState rhoConst;
        specie          specie;
        energy          sensibleEnthalpy;
    }

    mixture
    {
        specie
        {
            molWeight       20;
        }
        transport
        {
            kappa           0.01;
        }
        thermodynamics
        {
            Hf              0;
            Cp              15;
        }
        density
        {
            rho             80;
        }
    }

    radiation
    {
        radiationModel  opaqueSolid;
        absorptionEmissionModel none;
        scatterModel    none;
    }

    // Extrude model for new region

    extrudeModel        linearNormal;
    nLayers             50;
    expansionRatio      1;
    columnCells         false; //3D or 1D
    linearNormalCoeffs
    {
        thickness           0.02;
    }

}

If the thermal baffle is used on internal faces of the primary region, then the slave in this region is defined as :

Slave patch on primary region:

<slavePatchName>
{
    type                compressible::thermalBaffle;
    kappaMethod         fluidThermo;
    kappa               none;
    value               uniform 300;

Patches on baffle region:

bottom
{
    type                compressible::thermalBaffle;
    kappaMethod         solidThermo;
    kappa               none;
    value               uniform 300;
}

top
{
    type                compressible::thermalBaffle;
    kappaMethod         solidThermo;
    kappa               none;
    value               uniform 300;
}

See also: Foam::compressible::turbulentTemperatureCoupledBaffleMixedFvPatchScalarField Foam::regionModels::thermalBaffleModels::thermalBaffleModel

Source files

Definition at line 310 of file thermalBaffleFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ thermalBaffleFvPatchScalarField() [1/4]

thermalBaffleFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct from patch and internal field.

Definition at line 44 of file thermalBaffleFvPatchScalarField.C.

Referenced by thermalBaffleFvPatchScalarField::clone().

Here is the caller graph for this function:

◆ thermalBaffleFvPatchScalarField() [2/4]

thermalBaffleFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Construct from patch, internal field and dictionary.

Definition at line 82 of file thermalBaffleFvPatchScalarField.C.

References dict, objectRegistry::foundObject(), Foam::New(), Foam::foamVersion::patch, regionName, and fvMesh::time().

Here is the call graph for this function:

◆ thermalBaffleFvPatchScalarField() [3/4]

thermalBaffleFvPatchScalarField	(	const thermalBaffleFvPatchScalarField &	ptf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Construct by mapping given.

thermalBaffleFvPatchScalarField onto a new patch

Definition at line 59 of file thermalBaffleFvPatchScalarField.C.

◆ thermalBaffleFvPatchScalarField() [4/4]

thermalBaffleFvPatchScalarField	(	const thermalBaffleFvPatchScalarField &	ptf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct as copy setting internal field reference.

Definition at line 126 of file thermalBaffleFvPatchScalarField.C.

Member Function Documentation

◆ TypeName()

TypeName ( "compressible::thermalBaffle" )

Runtime type information.

◆ clone() [1/2]

virtual tmp<fvPatchScalarField> clone ( ) const

inlinevirtual

Construct and return a clone.

Reimplemented from turbulentTemperatureRadCoupledMixedFvPatchScalarField.

Definition at line 380 of file thermalBaffleFvPatchScalarField.H.

References thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField().

Here is the call graph for this function:

◆ clone() [2/2]

virtual tmp<fvPatchScalarField> clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Construct and return a clone setting internal field reference.

Reimplemented from turbulentTemperatureRadCoupledMixedFvPatchScalarField.

Definition at line 397 of file thermalBaffleFvPatchScalarField.H.

References thermalBaffleFvPatchScalarField::thermalBaffleFvPatchScalarField().

Here is the call graph for this function:

◆ autoMap()

void autoMap ( const fvPatchFieldMapper & m )

virtual

Map (and resize as needed) from self given a mapping object.

Definition at line 144 of file thermalBaffleFvPatchScalarField.C.

◆ rmap()

void rmap	(	const fvPatchScalarField &	ptf,
		const labelList &	addr
	)

virtual

Reverse map the given fvPatchField onto this fvPatchField.

Definition at line 153 of file thermalBaffleFvPatchScalarField.C.

◆ updateCoeffs()

void updateCoeffs ( )

virtual

Update the coefficients associated with the patch field.

Reimplemented from turbulentTemperatureRadCoupledMixedFvPatchScalarField.

Definition at line 255 of file thermalBaffleFvPatchScalarField.C.

References turbulentTemperatureRadCoupledMixedFvPatchScalarField::updateCoeffs().

Here is the call graph for this function:

◆ write()

void write ( Ostream & os ) const

virtual

Write.

Reimplemented from turbulentTemperatureRadCoupledMixedFvPatchScalarField.

Definition at line 271 of file thermalBaffleFvPatchScalarField.C.

References dictionary::get(), dictionary::subDict(), turbulentTemperatureRadCoupledMixedFvPatchScalarField::write(), Ostream::writeEntry(), dictionary::writeEntry(), and Ostream::writeEntryIfDifferent().

Here is the call graph for this function:

The documentation for this class was generated from the following files:

src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.H
src/regionModels/thermalBaffleModels/derivedFvPatchFields/thermalBaffle/thermalBaffleFvPatchScalarField.C

Public Member Functions

Additional Inherited Members

Detailed Description

Constructor & Destructor Documentation

◆ thermalBaffleFvPatchScalarField() [1/4]

◆ thermalBaffleFvPatchScalarField() [2/4]

◆ thermalBaffleFvPatchScalarField() [3/4]

◆ thermalBaffleFvPatchScalarField() [4/4]

Member Function Documentation

◆ TypeName()

◆ clone() [1/2]

◆ clone() [2/2]

◆ autoMap()

◆ rmap()

◆ updateCoeffs()

◆ write()