energyTransport.C

Go to the documentation of this file.

/*---------------------------------------------------------------------------*\
  =========                 |
  \\      /  F ield         | OpenFOAM: The Open Source CFD Toolbox
   \\    /   O peration     |
    \\  /    A nd           | www.openfoam.com
     \\/     M anipulation  |
-------------------------------------------------------------------------------
    Copyright (C) 2017-2021 OpenCFD Ltd.
-------------------------------------------------------------------------------
License
    This file is part of OpenFOAM.
 
    OpenFOAM is free software: you can redistribute it and/or modify it
    under the terms of the GNU General Public License as published by
    the Free Software Foundation, either version 3 of the License, or
    (at your option) any later version.
 
    OpenFOAM is distributed in the hope that it will be useful, but WITHOUT
    ANY WARRANTY; without even the implied warranty of MERCHANTABILITY or
    FITNESS FOR A PARTICULAR PURPOSE.  See the GNU General Public License
    for more details.
 
    You should have received a copy of the GNU General Public License
    along with OpenFOAM.  If not, see <http://www.gnu.org/licenses/>.
 
\*---------------------------------------------------------------------------*/
 
#include "energyTransport.H"
#include "surfaceFields.H"
#include "fvmDdt.H"
#include "fvmDiv.H"
#include "fvmLaplacian.H"
#include "fvmSup.H"
#include "turbulentTransportModel.H"
#include "turbulentFluidThermoModel.H"
#include "addToRunTimeSelectionTable.H"
 
// * * * * * * * * * * * * * * Static Data Members * * * * * * * * * * * * * //
 
namespace Foam
{
namespace functionObjects
{
    defineTypeNameAndDebug(energyTransport, 0);
 
    addToRunTimeSelectionTable
    (
        functionObject,
        energyTransport,
        dictionary
    );
}
}
 
 
// * * * * * * * * * * * * * Private Member Functions  * * * * * * * * * * * //
 
Foam::volScalarField& Foam::functionObjects::energyTransport::transportedField()
{
    if (!foundObject<volScalarField>(fieldName_))
    {
        auto tfldPtr = tmp<volScalarField>::New
        (
            IOobject
            (
                fieldName_,
                mesh_.time().timeName(),
                mesh_,
                IOobject::MUST_READ,
                IOobject::AUTO_WRITE
            ),
            mesh_
        );
        store(fieldName_, tfldPtr);
    }
 
    return lookupObjectRef<volScalarField>(fieldName_);
}
 
 
Foam::tmp<Foam::volScalarField>
Foam::functionObjects::energyTransport::kappaEff() const
{
    // Incompressible
    {
        typedef incompressible::turbulenceModel turbType;
 
        const turbType* turbPtr = findObject<turbType>
        (
            turbulenceModel::propertiesName
        );
 
        if (turbPtr)
        {
            return tmp<volScalarField>
            (
                new volScalarField
                (
                    kappa() + Cp()*turbPtr->nut()*rho()/Prt_
                )
            );
        }
    }
 
    FatalErrorInFunction
        << "Turbulence model not found" << exit(FatalError);
 
    return nullptr;
}
 
 
Foam::tmp<Foam::volScalarField>
Foam::functionObjects::energyTransport::rho() const
{
    auto trho = tmp<volScalarField>::New
    (
        IOobject
        (
            "trho",
            mesh_.time().timeName(),
            mesh_,
            IOobject::NO_READ,
            IOobject::NO_WRITE,
            false
        ),
        mesh_,
        rho_
    );
 
    if (phases_.size())
    {
        trho.ref() = lookupObject<volScalarField>(rhoName_);
    }
    return trho;
}
 
 
Foam::tmp<Foam::volScalarField>
Foam::functionObjects::energyTransport::Cp() const
{
    if (phases_.size())
    {
        tmp<volScalarField> tCp(phases_[0]*Cps_[0]);
 
        for (label i = 1; i < phases_.size(); i++)
        {
            tCp.ref() += phases_[i]*Cps_[i];
        }
        return tCp;
    }
 
    return tmp<volScalarField>::New
    (
        IOobject
        (
            "tCp",
            mesh_.time().timeName(),
            mesh_,
            IOobject::NO_READ,
            IOobject::NO_WRITE,
            false
        ),
        mesh_,
        Cp_
    );
}
 
 
Foam::tmp<Foam::volScalarField>
Foam::functionObjects::energyTransport::kappa() const
{
    if (phases_.size())
    {
        tmp<volScalarField> tkappa(phases_[0]*kappas_[0]);
 
        for (label i = 1; i < phases_.size(); i++)
        {
            tkappa.ref() += phases_[i]*kappas_[i];
        }
        return tkappa;
    }
 
    return tmp<volScalarField>::New
    (
        IOobject
        (
            "tkappa",
            mesh_.time().timeName(),
            mesh_,
            IOobject::NO_READ,
            IOobject::NO_WRITE,
            false
        ),
        mesh_,
        kappa_
    );
}
 
// * * * * * * * * * * * * * * * * Constructors  * * * * * * * * * * * * * * //
 
Foam::functionObjects::energyTransport::energyTransport
(
    const word& name,
    const Time& runTime,
    const dictionary& dict
)
:
    fvMeshFunctionObject(name, runTime, dict),
    fieldName_(dict.getOrDefault<word>("field", "T")),
    phiName_(dict.getOrDefault<word>("phi", "phi")),
    rhoName_(dict.getOrDefault<word>("rho", "rho")),
    nCorr_(0),
    schemesField_("unknown-schemesField"),
    fvOptions_(mesh_),
    multiphaseThermo_(dict.subOrEmptyDict("phaseThermos")),
    Cp_("Cp", dimEnergy/dimMass/dimTemperature, 0, dict),
    kappa_
    (
        "kappa",
        dimEnergy/dimTime/dimLength/dimTemperature,
        0,
        dict
    ),
    rho_("rhoInf", dimDensity, 0, dict),
    Prt_("Prt", dimless, 1, dict),
    rhoCp_
    (
        IOobject
        (
            "rhoCp",
            mesh_.time().timeName(),
            mesh_,
            IOobject::NO_READ,
            IOobject::NO_WRITE,
            false
        ),
        mesh_,
        dimensionedScalar(dimEnergy/dimTemperature/dimVolume, Zero)
    )
{
    read(dict);
 
    // If the flow is multiphase
    if (!multiphaseThermo_.empty())
    {
        Cps_.setSize(multiphaseThermo_.size());
        kappas_.setSize(Cps_.size());
        phaseNames_.setSize(Cps_.size());
 
        label phasei = 0;
        forAllConstIters(multiphaseThermo_, iter)
        {
            const word& key = iter().keyword();
 
            if (!multiphaseThermo_.isDict(key))
            {
                FatalErrorInFunction
                    << "Found non-dictionary entry " << iter()
                    << " in top-level dictionary " << multiphaseThermo_
                    << exit(FatalError);
            }
 
            const dictionary& dict = multiphaseThermo_.subDict(key);
 
            phaseNames_[phasei] = key;
 
            Cps_.set
            (
                phasei,
                new dimensionedScalar
                (
                    "Cp",
                    dimEnergy/dimMass/dimTemperature,
                    dict
                )
            );
 
            kappas_.set
            (
                phasei,
                new dimensionedScalar //[J/m/s/K]
                (
                    "kappa",
                    dimEnergy/dimTime/dimLength/dimTemperature,
                    dict
                )
            );
 
            ++phasei;
        }
 
        phases_.setSize(phaseNames_.size());
        forAll(phaseNames_, i)
        {
            phases_.set
            (
                i,
                mesh_.getObjectPtr<volScalarField>(phaseNames_[i])
            );
        }
 
        rhoCp_ = rho()*Cp();
        rhoCp_.oldTime();
    }
    else
    {
        if (Cp_.value() == 0.0 || kappa_.value() == 0.0)
        {
            FatalErrorInFunction
                << " Multiphase thermo dictionary not found and Cp/kappa "
                << " for single  phase are zero. Please entry either"
                << exit(FatalError);
        }
 
    }
 
    // Force creation of transported field so any BCs using it can
    // look it up
    volScalarField& s = transportedField();
    s.correctBoundaryConditions();
}
 
 
// * * * * * * * * * * * * * * * * Destructor  * * * * * * * * * * * * * * * //
 
Foam::functionObjects::energyTransport::~energyTransport()
{}
 
 
// * * * * * * * * * * * * * * * Member Functions  * * * * * * * * * * * * * //
 
bool Foam::functionObjects::energyTransport::read(const dictionary& dict)
{
    fvMeshFunctionObject::read(dict);
 
    dict.readIfPresent("phi", phiName_);
    dict.readIfPresent("rho", rhoName_);
 
    schemesField_ = dict.getOrDefault("schemesField", fieldName_);
 
    dict.readIfPresent("nCorr", nCorr_);
 
    if (dict.found("fvOptions"))
    {
        fvOptions_.reset(dict.subDict("fvOptions"));
    }
 
    return true;
}
 
 
bool Foam::functionObjects::energyTransport::execute()
{
    volScalarField& s = transportedField();
 
    Log << type() << " execute: " << s.name() << endl;
 
    const surfaceScalarField& phi =
        mesh_.lookupObject<surfaceScalarField>(phiName_);
 
    // Calculate the diffusivity
    const volScalarField kappaEff("kappaEff", this->kappaEff());
 
    word divScheme("div(phi," + schemesField_ + ")");
    word laplacianScheme
    (
        "laplacian(kappaEff," + schemesField_ + ")"
    );
 
    // Set under-relaxation coeff
    scalar relaxCoeff = 0.0;
    if (mesh_.relaxEquation(schemesField_))
    {
        relaxCoeff = mesh_.equationRelaxationFactor(schemesField_);
    }
 
    if (phi.dimensions() == dimMass/dimTime)
    {
        rhoCp_ = rho()*Cp();
        const surfaceScalarField rhoCpPhi(fvc::interpolate(Cp())*phi);
 
        for (label i = 0; i <= nCorr_; i++)
        {
            fvScalarMatrix sEqn
            (
                fvm::ddt(rhoCp_, s)
              + fvm::div(rhoCpPhi, s, divScheme)
              - fvm::Sp(fvc::ddt(rhoCp_) + fvc::div(rhoCpPhi), s)
              - fvm::laplacian(kappaEff, s, laplacianScheme)
             ==
                fvOptions_(rhoCp_, s)
            );
 
            sEqn.relax(relaxCoeff);
 
            fvOptions_.constrain(sEqn);
 
            sEqn.solve(mesh_.solverDict(schemesField_));
        }
    }
    else if (phi.dimensions() == dimVolume/dimTime)
    {
        dimensionedScalar rhoCp(rho_*Cp_);
 
        const surfaceScalarField CpPhi(rhoCp*phi);
 
        auto trhoCp = tmp<volScalarField>::New
        (
            IOobject
            (
                "trhoCp",
                mesh_.time().timeName(),
                mesh_,
                IOobject::NO_READ,
                IOobject::NO_WRITE
            ),
            mesh_,
            rhoCp
        );
 
        for (label i = 0; i <= nCorr_; i++)
        {
            fvScalarMatrix sEqn
            (
                fvm::ddt(rhoCp, s)
              + fvm::div(CpPhi, s, divScheme)
              - fvm::laplacian(kappaEff, s, laplacianScheme)
             ==
                fvOptions_(trhoCp.ref(), s)
            );
 
            sEqn.relax(relaxCoeff);
 
            fvOptions_.constrain(sEqn);
 
            sEqn.solve(mesh_.solverDict(schemesField_));
        }
    }
    else
    {
        FatalErrorInFunction
            << "Incompatible dimensions for phi: " << phi.dimensions() << nl
            << "Dimensions should be " << dimMass/dimTime << " or "
            << dimVolume/dimTime << exit(FatalError);
    }
 
    Log << endl;
 
    return true;
}
 
 
bool Foam::functionObjects::energyTransport::write()
{
    return true;
}
 
 
// ************************************************************************* //