This boundary condition provides a total pressure condition. Four variants are possible: More...

Inheritance diagram for totalPressureFvPatchScalarField:

Collaboration diagram for totalPressureFvPatchScalarField:

Public Member Functions
	TypeName ("totalPressure")
	Runtime type information. More...

	totalPressureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &)
	Construct from patch and internal field. More...

	totalPressureFvPatchScalarField (const fvPatch &, const DimensionedField< scalar, volMesh > &, const dictionary &)
	Construct from patch, internal field and dictionary. More...

	totalPressureFvPatchScalarField (const totalPressureFvPatchScalarField &, const fvPatch &, const DimensionedField< scalar, volMesh > &, const fvPatchFieldMapper &)
	Construct by mapping given totalPressureFvPatchScalarField. More...

	totalPressureFvPatchScalarField (const totalPressureFvPatchScalarField &)
	Construct as copy. More...

virtual tmp< fvPatchScalarField >	clone () const
	Construct and return a clone. More...

	totalPressureFvPatchScalarField (const totalPressureFvPatchScalarField &, const DimensionedField< scalar, volMesh > &)
	Construct as copy setting internal field reference. More...

virtual tmp< fvPatchScalarField >	clone (const DimensionedField< scalar, volMesh > &iF) const
	Construct and return a clone setting internal field reference. More...

const word &	UName () const
	Return the name of the velocity field. More...

word &	UName ()
	Return reference to the name of the velocity field. More...

const word &	phiName () const
	Return the name of the flux field. More...

word &	phiName ()
	Return reference to the name of the flux field. More...

const word &	rhoName () const
	Return the name of the density field. More...

word &	rhoName ()
	Return reference to the name of the density field. More...

const word &	psiName () const
	Return the name of the compressibility field. More...

word &	psiName ()
	Return reference to the name of the compressibility field. More...

scalar	gamma () const
	Return the heat capacity ratio. More...

scalar &	gamma ()
	Return reference to the heat capacity ratio to allow adjustment. More...

const scalarField &	p0 () const
	Return the total pressure. More...

scalarField &	p0 ()
	Return reference to the total pressure to allow adjustment. More...

virtual void	autoMap (const fvPatchFieldMapper &)
	Map (and resize as needed) from self given a mapping object. More...

virtual void	rmap (const fvPatchScalarField &, const labelList &)
	Reverse map the given fvPatchField onto this fvPatchField. More...

virtual void	updateCoeffs (const scalarField &p0p, const vectorField &Up)
	Update the coefficients associated with the patch field. More...

virtual void	updateCoeffs ()
	Update the coefficients associated with the patch field. More...

virtual void	write (Ostream &) const
	Write. More...

Detailed Description

This boundary condition provides a total pressure condition. Four variants are possible:

1. incompressible subsonic:

\[ p_p = p_0 - 0.5 |U|^2 \]

where

\( p_p \)	=	incompressible pressure at patch [m2/s2]
\( p_0 \)	=	incompressible total pressure [m2/s2]
\( U \)	=	velocity

2. compressible subsonic:

\[ p_p = p_0 - 0.5 \rho |U|^2 \]

where

\( p_p \)	=	pressure at patch [Pa]
\( p_0 \)	=	total pressure [Pa]
\( \rho \)	=	density [kg/m3]
\( U \)	=	velocity

3. compressible transonic ( \(\gamma = 1\)):

\[ p_p = \frac{p_0}{1 + 0.5 \psi |U|^2} \]

where

\( p_p \)	=	pressure at patch [Pa]
\( p_0 \)	=	total pressure [Pa]
\( G \)	=	coefficient given by \(\frac{\gamma}{1-\gamma}\)

4. compressible supersonic ( \(\gamma > 1\)):

\[ p_p = \frac{p_0}{(1 + 0.5 \psi G |U|^2)^{\frac{1}{G}}} \]

where

\( p_p \)	=	pressure at patch [Pa]
\( p_0 \)	=	total pressure [Pa]
\( \gamma \)	=	ratio of specific heats (Cp/Cv)
\( \psi \)	=	compressibility [m2/s2]
\( G \)	=	coefficient given by \(\frac{\gamma}{1-\gamma}\)

The modes of operation are set by the dimensions of the pressure field to which this boundary condition is applied, the psi entry and the value of gamma:

Mode	dimensions	psi	gamma
`incompressible` subsonic	p/rho
`compressible` subsonic	p	none
`compressible` transonic	p	psi	1
`compressible` supersonic	p	psi	> 1

Usage

Property	Description	Required	Default value
`U`	Velocity field name	no	U
`phi`	Flux field name	no	phi
`rho`	Density field name	no	rho
`psi`	Compressibility field name	no	none
`gamma`	(Cp/Cv)	no	1
`p0`	Total pressure	yes

Example of the boundary condition specification:

    <patchName>
    {
        type            totalPressure;
        p0              uniform 1e5;
    }

See also: Foam::fixedValueFvPatchField

Source files

Definition at line 256 of file totalPressureFvPatchScalarField.H.

Constructor & Destructor Documentation

◆ totalPressureFvPatchScalarField() [1/5]

totalPressureFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct from patch and internal field.

Definition at line 38 of file totalPressureFvPatchScalarField.C.

◆ totalPressureFvPatchScalarField() [2/5]

totalPressureFvPatchScalarField	(	const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const dictionary &	dict
	)

Construct from patch, internal field and dictionary.

Definition at line 54 of file totalPressureFvPatchScalarField.C.

References dict, dictionary::found(), fvPatchField< Type >::operator=(), p, and UList< T >::size().

Here is the call graph for this function:

◆ totalPressureFvPatchScalarField() [3/5]

totalPressureFvPatchScalarField	(	const totalPressureFvPatchScalarField &	ptf,
		const fvPatch &	p,
		const DimensionedField< scalar, volMesh > &	iF,
		const fvPatchFieldMapper &	mapper
	)

Construct by mapping given totalPressureFvPatchScalarField.

onto a new patch

Definition at line 83 of file totalPressureFvPatchScalarField.C.

◆ totalPressureFvPatchScalarField() [4/5]

totalPressureFvPatchScalarField ( const totalPressureFvPatchScalarField & tppsf )

Construct as copy.

Definition at line 101 of file totalPressureFvPatchScalarField.C.

◆ totalPressureFvPatchScalarField() [5/5]

totalPressureFvPatchScalarField	(	const totalPressureFvPatchScalarField &	tppsf,
		const DimensionedField< scalar, volMesh > &	iF
	)

Construct as copy setting internal field reference.

Definition at line 116 of file totalPressureFvPatchScalarField.C.

Member Function Documentation

◆ TypeName()

TypeName ( "totalPressure" )

Runtime type information.

◆ clone() [1/2]

virtual tmp< fvPatchScalarField > clone ( ) const

inlinevirtual

Construct and return a clone.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 322 of file totalPressureFvPatchScalarField.H.

◆ clone() [2/2]

virtual tmp< fvPatchScalarField > clone ( const DimensionedField< scalar, volMesh > & iF ) const

inlinevirtual

Construct and return a clone setting internal field reference.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 338 of file totalPressureFvPatchScalarField.H.

◆ UName() [1/2]

const word & UName ( ) const

inline

Return the name of the velocity field.

Definition at line 355 of file totalPressureFvPatchScalarField.H.

◆ UName() [2/2]

word & UName ( )

inline

Return reference to the name of the velocity field.

to allow adjustment

Definition at line 362 of file totalPressureFvPatchScalarField.H.

◆ phiName() [1/2]

const word & phiName ( ) const

inline

Return the name of the flux field.

Definition at line 368 of file totalPressureFvPatchScalarField.H.

◆ phiName() [2/2]

word & phiName ( )

inline

Return reference to the name of the flux field.

to allow adjustment

Definition at line 375 of file totalPressureFvPatchScalarField.H.

◆ rhoName() [1/2]

const word & rhoName ( ) const

inline

Return the name of the density field.

Definition at line 381 of file totalPressureFvPatchScalarField.H.

◆ rhoName() [2/2]

word & rhoName ( )

inline

Return reference to the name of the density field.

to allow adjustment

Definition at line 388 of file totalPressureFvPatchScalarField.H.

◆ psiName() [1/2]

const word & psiName ( ) const

inline

Return the name of the compressibility field.

Definition at line 394 of file totalPressureFvPatchScalarField.H.

◆ psiName() [2/2]

word & psiName ( )

inline

Return reference to the name of the compressibility field.

to allow adjustment

Definition at line 401 of file totalPressureFvPatchScalarField.H.

◆ gamma() [1/2]

scalar gamma ( ) const

inline

Return the heat capacity ratio.

Definition at line 407 of file totalPressureFvPatchScalarField.H.

◆ gamma() [2/2]

scalar & gamma ( )

inline

Return reference to the heat capacity ratio to allow adjustment.

Definition at line 413 of file totalPressureFvPatchScalarField.H.

◆ p0() [1/2]

const scalarField & p0 ( ) const

inline

Return the total pressure.

Definition at line 419 of file totalPressureFvPatchScalarField.H.

◆ p0() [2/2]

scalarField & p0 ( )

inline

Return reference to the total pressure to allow adjustment.

Definition at line 425 of file totalPressureFvPatchScalarField.H.

◆ autoMap()

void autoMap ( const fvPatchFieldMapper & m )

virtual

Map (and resize as needed) from self given a mapping object.

Definition at line 134 of file totalPressureFvPatchScalarField.C.

◆ rmap()

void rmap	(	const fvPatchScalarField &	ptf,
		const labelList &	addr
	)

virtual

Reverse map the given fvPatchField onto this fvPatchField.

Definition at line 144 of file totalPressureFvPatchScalarField.C.

◆ updateCoeffs() [1/2]

void updateCoeffs	(	const scalarField &	p0p,
		const vectorField &	Up
	)

virtual

Update the coefficients associated with the patch field.

using the given patch total pressure and velocity fields

Definition at line 159 of file totalPressureFvPatchScalarField.C.

References Foam::dimDensity, Foam::dimPressure, Foam::exit(), Foam::FatalError, FatalErrorInFunction, Foam::magSqr(), Foam::nl, Foam::operator==(), Foam::pos0(), Foam::pow(), and rho.

Here is the call graph for this function:

◆ updateCoeffs() [2/2]

void updateCoeffs ( )

virtual

Update the coefficients associated with the patch field.

Reimplemented in fanPressureFvPatchScalarField, and rotatingTotalPressureFvPatchScalarField.

Definition at line 236 of file totalPressureFvPatchScalarField.C.

References p0, and UName().

Referenced by fanPressureFvPatchScalarField::updateCoeffs(), and rotatingTotalPressureFvPatchScalarField::updateCoeffs().

Here is the call graph for this function:

Here is the caller graph for this function:

◆ write()

void write ( Ostream & os ) const

virtual

Write.

Reimplemented in rotatingTotalPressureFvPatchScalarField, and fanPressureFvPatchScalarField.

Definition at line 246 of file totalPressureFvPatchScalarField.C.

References os(), ObukhovLength::write(), Ostream::writeEntry(), and Ostream::writeEntryIfDifferent().

Here is the call graph for this function:

The documentation for this class was generated from the following files:

src/finiteVolume/fields/fvPatchFields/derived/totalPressure/totalPressureFvPatchScalarField.H
src/finiteVolume/fields/fvPatchFields/derived/totalPressure/totalPressureFvPatchScalarField.C

Public Member Functions

Detailed Description

Constructor & Destructor Documentation

◆ totalPressureFvPatchScalarField() [1/5]

◆ totalPressureFvPatchScalarField() [2/5]

◆ totalPressureFvPatchScalarField() [3/5]

◆ totalPressureFvPatchScalarField() [4/5]

◆ totalPressureFvPatchScalarField() [5/5]

Member Function Documentation

◆ TypeName()

◆ clone() [1/2]

◆ clone() [2/2]

◆ UName() [1/2]

◆ UName() [2/2]

◆ phiName() [1/2]

◆ phiName() [2/2]

◆ rhoName() [1/2]

◆ rhoName() [2/2]

◆ psiName() [1/2]

◆ psiName() [2/2]

◆ gamma() [1/2]

◆ gamma() [2/2]

◆ p0() [1/2]

◆ p0() [2/2]

◆ autoMap()

◆ rmap()

◆ updateCoeffs() [1/2]

◆ updateCoeffs() [2/2]

◆ write()